Inventor Simplify: How to Share a Model Without Giving Away Your Design
2026-11-14 15:32
Inventor Simplify is the Autodesk Inventor command that turns a detailed assembly or part into a lighter model with internal components and small features removed, so a supplier or client gets the shape they need without the design work behind it. Autodesk’s own help page for the command (Inventor 2026 Help, read 14 November 2026) names the purpose in plain words: protect intellectual property by removing features and internal components.
This guide covers what the command does, which settings decide how much of your design leaves the building, what changed in Inventor 2025 and 2026, and what to check before a simplified file goes out. For the wider picture of what goes wrong when CAD files travel, start with our overview of the risks of sharing CAD files.
What does Inventor Simplify do?
Simplify builds a new solid or composite-surface model from the active assembly. It removes the components and features you choose, wraps others in simple envelopes and writes the result to a simplified part. Since Inventor 2026, part files have their own Simplify command too, on the 3D Model tab in the Simplification panel. The command is not available in Express mode, so open large assemblies in full mode before you start (Inventor 2027 Help, Create a Simplified Part from an Assembly, read 14 November 2026).
Shrinkwrap, the older name that many engineers still type into search, is now a legacy item. Older shrinkwrapped parts are edited from the Simplify panel, so a team that learned Shrinkwrap years ago can switch without rebuilding its old files.
Which Simplify settings protect your IP?
Five groups of settings decide how much of your design survives in the output. Here is what each one does.
1. Envelopes
Envelopes swap detailed geometry for a simple shape. The scope can be All in One Envelope, Each Top Level Component or Each Part, and the shape can be an Orthogonal Bounding Box, an Oriented Minimum Bounding Box or, since Inventor 2025, an Oriented Minimum Bounding Cylinder. A gearbox sent as one bounding box still shows the space it takes and tells a competitor nothing about the gears inside.
2. Remove components
You can remove parts by selection or by size. Every part that fits inside a bounding box with the maximum diagonal you set drops out of the model. Use it for fasteners, small purchased parts and anything the recipient has no reason to see.
3. Remove internal parts and fill voids
Remove internal parts is on by default. Inventor checks visibility from 14 directions (6 orthographic and 8 isometric) and drops whatever it cannot see from any of them. Fill internal voids closes the internal void shells in the simplified solid, so hollow castings and hidden cavities stop showing up when someone cuts a section through your model.
4. Remove features
Holes, fillets, chamfers, pockets, embosses and tunnels (slots) each get their own rule: None, All, Range (up to a maximum size) or Preserve. Keep the holes the recipient needs for mounting and strip the rest.
5. Output
Choose New Part File or Substitute. A new part file is a derived part, and Edit Simplification keeps working as long as the link to the assembly stays in place. Substitute writes the result into a Substitute Model State of the parent assembly, which suits a light stand-in inside your own projects. IPT styles are a single solid without seams, a single solid with seams, one solid per body or a single composite surface. The Associative option ties the result to a design view, and the Master view can’t be used for it. Revit users can also write RVT or RFA files.
Which Simplify preset should you start from?
Autodesk ships presets that set the size filter, feature removal, void filling and internal-part removal in one click (Inventor 2026 Help, Simplify presets, read 14 November 2026). The right-hand column is our advice from CAD teams sharing files with suppliers.
Preset
What it does
Good fit
Remove the most detail
Puts everything in envelopes, size filter 400 mm, fills voids and removes internal parts
Space claims for layouts and factory planning
Remove moderate detail
Size filter 300 mm, removes all holes, fillets, chamfers, pockets and embosses, fills voids and removes internal parts
Customer models, sales visuals, tender drawings
Remove the least detail
Size filter 200 mm, removes features within set size ranges, fills voids and removes internal parts
Suppliers who need mounting holes and interfaces
No Simplification
Applies no simplification until you set your own rules
Custom rules for a single customer or project
What changed in Inventor 2025 and 2026?
Inventor 2025 added the Oriented Minimum Bounding Cylinder envelope. With All in One Envelope, Inventor also shows the cylinder’s diameter and height, which is handy for shafts, rollers and drums (Inventor 2025 What’s New, read 14 November 2026).
Inventor 2026 brought Simplify into part files. A Simplify feature appears in the browser, presets are shared between parts and assemblies, a Preview button shows the result before you commit, and Whole Part envelope sizes are stored as read-only parameters. Part-level Simplify can exclude bodies by selection or size, remove internal bodies and be controlled with model states. The same release added IFC 4x3 for Simplify to Revit (Inventor 2026 What’s New, read 14 November 2026). The 2027 and 2027.1 What’s New pages for assemblies list no Simplify changes.
How do you simplify an assembly for a supplier, step by step?
Save a copy of the assembly and write down what the recipient needs: overall size, mounting interfaces, a visual model or a body for simulation.
Start Simplify and pick the preset closest to that need.
Put purchased parts, and anything whose internals are your know-how, into envelopes.
Remove components by size to drop fasteners and small parts.
Leave Remove internal parts and Fill internal voids switched on.
Set the feature rules: Preserve the holes the recipient needs and remove the rest.
Choose New Part File for a file that will leave the company, or Substitute when you only want a light stand-in inside your own assembly.
Open the result on its own, check it with the list below, then export it to the format the recipient asked for.
Teams that send the same kind of model every week can batch the job: Autodesk documents a Task Scheduler workflow for simplifying assemblies, and our Autodesk Inventor automation guide shows where iLogic and add-ins fit around it.
What should you check before you send a simplified file?
Simplify reduces geometry. Autodesk’s help pages say nothing about iProperties, sketches or other metadata, so treat them as still present until you have checked them yourself.
Open the simplified part on its own and cut a section in two directions to confirm that nothing internal remains.
Read the iProperties: author, company, project, part numbers and custom properties. Clear what the recipient doesn’t need. Our guide to CAD file metadata and privacy lists the fields that leak most.
Break the link to the source assembly before export, so the file no longer depends on your original.
Pick the neutral format on purpose. Inventor’s STEP export offers Application Protocol 203, 214 and 242; AP242 carries PMI and is not available for assemblies, and an assembly saves to a single STEP file (Inventor 2026 Help, STEP translator, read 14 November 2026). Leave sketches out unless the recipient asked for them.
A simplified model still shows the outside of your product. The envelope and feature settings decide how much shape leaves, and the shape that leaves can still be measured, copied and reverse-engineered. Converting to PDF or sending a single part runs into the same wall, as our pieces on geometry alienation in CAD conversion and CAD to PDF conversion limits show.
Shrinkwrap is now a legacy item. Older shrinkwrapped parts are edited from the Simplify panel, and new work uses the Simplify command.
Can I simplify a single part in Inventor?
Yes. Since Inventor 2026, part files have their own Simplify command on the 3D Model tab, with presets shared with assemblies, a Preview button and model state control.
Does Inventor Simplify remove iProperties?
Autodesk’s help pages don’t say so. Check the iProperties of the simplified part by hand and clear anything the recipient doesn’t need before you send it.
Is the simplified part still linked to my assembly?
A simplified part is a derived part file, and Edit Simplification works while the link stays in place. Break the link before the file leaves your company.
What is the difference between a simplified part and a substitute model state?
A simplified part is a separate IPT file you can export and send. A substitute model state stores the simplified result inside your parent assembly as a light stand-in for your own projects.
Which STEP protocol should I use for a simplified model?
Inventor offers AP203, AP214 and AP242. AP242 carries PMI and is not available for assemblies, so assemblies go out as AP203 or AP214 in a single STEP file.
Does a simplified model fully protect my design?
No. The outside shape still leaves with the file and can be measured or copied. Combine Simplify with contracts, view-only access and a dated proof of authorship such as a BORIS certificate.
Can I run Simplify on many assemblies at once?
Yes. Autodesk documents a Task Scheduler workflow for simplifying assemblies in batches, including filling internal voids and creating a substitute model state.